Defining Skipped References
To define any skipped references for your notch or punch you use the same options and prompts originally used when you began placing the feature in your design.
After you have answered each UDF placement prompt, if you intentionally skipped any references an Information Window opens and the CONFIRMATION menu appears. Click Confirm to redefine the skipped references on the base part, or the actual notch or punch. You enter the feature creation environment. The dialog box for the feature with skipped references appears.
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 To return to the references you skipped, click Cancel. Then select the references you need to specify from the GP REFS menu. You return to the original UDF prompt. The feature dialog box opens and lists skipped references and variable elements. To reconcile the skipped reference, highlight the element to fix and click Define on the feature dialog box. |
Depending on the type of reference skipped you are defining, you need to use one of the following procedures to define your references:
• The skipped reference is used by an element other than a sketched section.
For the skipped reference, you enter into the feature creation environment enabling you to redefine the element that uses the skipped references.
• If the skipped reference is a sketching plane or horizontal reference for a section.
If you redefine a sketching plane or horizontal references, the dialog box for the feature using the skipped reference appears. From the dialog box, select the Section element and click Define. Click Sketch Plane and define the reference as appropriate.
• If the skipped reference is used by a section other than the sketching plane or horizontal reference.
If you must redefine a section reference (for example, edges used as dimensioning references), the dialog box for the feature using the skipped reference appears. Select the Section element and click Define. Choose the appropriate sketch option from the Section menu; the part reappears in the sketching view and the SECTION PLACE menu appears with the following options:
◦ DragAndDrop—Places the existing UDF section directly on the part. When you enable this option the section is outlined in red. Use the mouse to move the section to its new location. Place the section by left-clicking the mouse. Dimension the section to the part and regenerate. The middle mouse button quits section placement.
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The DragAndDrop option is not available for sections fully aligned or created with the Use Edge option.
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◦ Create New—Discards the existing UDF section and creates a new section. Select Confirm to verify your action. Sketch a new section.
When you redefine a missing reference used by several features double check to see if:
• The skipped reference has a single prompt for all features. You must redefine the reference for each use. For example, if you use an edge to place a hole and a cut, and you set up a single prompt for both features, you must reselect the reference edge for both the hole and the cut if you skip the edge reference when placing the notch or punch.
• The skipped reference has individual prompts for all features. You only have to redefine the reference for the feature where it is skipped.