Part Modeling > Engineering Features > Round > Piece Management > To Extend Round Geometry
To Extend Round Geometry
1. Select the references for the round and click Model > Round. The Round tab opens and round preview geometry appears.
2. Open the Pieces tab and select the round piece to extend in the Pieces table. Handles appear on the piece ends.
* If you have a closed-loop round set, you need to open it by removing a patch. After you select the piece to extend, select the patch to remove it. The patch is removed and handles appear.
3. Drag a handle to extend the piece. As you drag, the potential extension of the round piece appears. Follow the extension up to the patch where you want to extend the piece. The system extends the round piece up to the patch. Notice that Edited appears in the Pieces table for the selected piece. Repeat the process if needed.
4. To extend another round piece, repeat step 2 and step 3.
5. To return the piece to its original state, select Included in the Pieces table or on the Pieces tab shortcut menu.
6. The extended round piece is complete. Close the Pieces tab to activate Sets mode and continue to work with rounds.
7. When completed, click .
If you extended multiple pieces in the current round set and want to quickly restore all of them to their original state, select All included on the Pieces tab shortcut menu.
To quickly locate a piece on your model, place your cursor over each piece in the Pieces table, and it is dynamically highlighted in the graphics window.