Part Modeling > Engineering Features > Round > To Create a Full Round
To Create a Full Round
If you are using two surfaces to create a Full round, refer to To Create a Surface-to-Surface Full Round.
1. In the graphics window, select the references from which to create the round. If you use only edge references, the edges must share a common surface. Notice that the round propagates across tangent neighbors until it encounters a break in tangency. However, if you use a One-by-One chain, the round does not propagate across tangent neighbors.
2. Click Model > Round. The Round tab opens, and preview geometry is shown. Notice that the selected references are in the References collector on the Sets tab.
3. Click Full round on the Sets tab, or in the graphics window, right-click and choose Full round from the shortcut menu. Preview geometry of the Full round is shown.
* You can select Full Round again to restore the round to its previous state.
4. Click .
If you are using a chain as a reference and you want to modify it, click Details on the Sets tab and use the Chain dialog box.
As you work in the graphics window, you can use Clear from the shortcut menu to clear all references from the active collector.
To remove a reference from within a collector, select the reference that you want to remove, and with your cursor still in the collector, right-click and choose Remove from the shortcut menu.
To easily create a round as you work in the graphics window, select edge references, right-click and choose Round Edges from the shortcut menu. The Round tool opens enabling you to continue working with the round. Note that this command is available only if you select edge references.