Part Modeling > Engineering Features > Hole > Simple Holes > To Define Simple Hole Depth by Snapping to a Reference
To Define Simple Hole Depth by Snapping to a Reference
In addition to dragging depth handles, or typing or selecting depth values, you can define Simple hole depth by snapping to a reference. This procedure does not apply to Sketched or Standard holes.
1. Select the approximate hole location on the model. This is your primary placement reference. The selection is highlighted.
2. Click Model > Hole. The Hole tab opens and preview geometry of the hole is displayed.
3. Click to create a Straight hole.
4. Hold down the SHIFT key and drag the depth handle and snap it to a reference. As you drag, notice each available reference is pre-highlighted as your pointer moves over it. This enables you to target the correct reference. After you snap the handle, the system does the following:
Replaces the default depth handle () with the snapped depth handle ().
Selects the To Selected depth option on the Hole tab and the Shape tab.
Populates the Depth Reference collector on the Hole tab to indicate that an item has been selected. The same collector on the Shape tab contains the selected reference.
5. To redefine the depth, hold down the SHIFT key and drag the depth handle to unsnap it from the reference. Notice that the system selects the Blind default depth option on the Hole tab and replaces the snapped depth handle () with the default depth handle (). You can now snap the depth handle to another reference, drag the handle to a preferred depth, or type or select a new depth value using the depth boxes from either the graphics window or from the Hole tab.
6. To define the hole depth for a second side (side-2), repeat the previous two steps using the side-2 depth handle.
7. The Simple hole depth is defined. Click to create the hole and close the Hole tool.
To reverse the hole depth direction, click Flip on the shortcut menu or on the Placement tab. Note that Flip is only available for Simple holes that use the Blind, To Next, or Through All depth option.
To use a datum point or datum plane as a reference, but one is not present, you can create one without closing the Hole tool by clicking Hole > Datum > Point or Hole > Datum > Plane. The Hole tool pauses.
As you work in the graphics window, you can use Clear from the shortcut menu to clear all references from the active collector.
To remove a reference from within a collector, select a reference in a collector, right-click, and choose Remove from the shortcut menu.
You can always increase or limit the available references being highlighted by using the Selection Filter box.
You can also click the middle mouse button to create the hole.