Part Modeling > Engineering Features > Hole > Standard Holes > To Create a Drilled Hole
To Create a Drilled Hole
1. Click Model > Hole. The Hole tab opens with the default hole type set to Simple hole, and the default Placement Type set to Linear.
2. Click to change the hole type to Standard hole. The Standard hole options are displayed, with tapping selected by default.
3. Clear tapping options by clicking . The Hole tab layout changes, and clearance hole and drilled hole are displayed.
4. Click to change the hole profile to drilled.
5. Select a surface on the model where you want to place the hole. The selection is highlighted. This is your placement reference.
* You can also select the placement reference before you activate the hole tool.
6. To change the hole placement type, select a new type from the placement Type box on the Placement tab.
7. Drag the offset placement reference handles to the appropriate references to constrain the hole. As you drag each handle, the available references are highlighted as your pointer moves over them. The system automatically snaps the handle to the reference and adds them to the Offset References collector on the Placement tab.
8. To orient the hole to be parallel to or perpendicular to a reference:
a. Click the Placement tab, click the Hole orientation collector, and select a planar, axial, or linear reference.
b. Select either Parallel or Perpendicular from the list.
9. Select the desired hole chart in the box adjacent to Thread Type. Thread Type enables you to select industry-standard hole charts (ISO, UNC, or UNF).
10. Type or select a screw size in the box adjacent to .
* If you enter a screw size that is not listed, the system selects the closest screw size. You can also drag the hole diameter handle to select a screw size.
11. To define the hole depth, select a depth option from the Depth Options list, or drag the depth handle in the graphics window.
* To define a new depth by dragging the depth handle, or by typing or selecting a new value, you must select the Blind depth option.
12. To add countersink, click .
13. To add counterbore, click .
14. To ensure that the entire top of the hole intersects the outside of the solid geometry, on the Shape tab, make sure that the Top Clearance check box is selected.
15. Click .