Creo Flexible Modeling > Recognizing Geometry Patterns > About the Pattern Recognition Feature User Interface
  
About the Pattern Recognition Feature User Interface
The Pattern Recognition tab consists of commands, tabs, and shortcut menus. Select the pattern leader geometry and click Flexible Modeling > Pattern Recognition to open the Pattern Recognition tab.
Shortcut Menus
Right-click the graphics window to access shortcut menu commands.
Pattern leader surfaces—Activates collection of the surfaces that define the leader of the geometry pattern to be recognized.
Pattern leader curves and datums—Activates collection of the curves and datums that define the leader of the geometry pattern to be recognized. Datum coordinate systems cannot be selected.
Allow Edit check box—Edits the number of pattern members and the spacing between pattern members for direction or axis patterns. Removes the existing pattern surfaces, and recreates the pattern using only the surfaces that are recognized as part of the pattern.
Transform selected attachment rounds/chamfers—Includes in the pattern recognition the selected rounds and chamfers that attach the pattern leader geometry to the model. If not checked, the selected attaching rounds and chamfers are removed and optionally recreated.
Commands
Pattern type menu—Sets the geometry pattern recognition in relation to the geometry selected as the pattern leader.
Identical—Recognizes patterns whose members have identical surfaces, and the intersection edges between the pattern members and the surrounding geometry are identical.
Similar—Recognizes patterns whose members have identical surfaces, but their intersection edges with the surrounding geometry can vary.
Recognized geometry menu—Selects which geometry pattern is the recognized pattern. The following pattern types are available:
Direction pattern
1—Shows either the translation or rotation pattern creation method in the first direction.
Instances—Sets the number of recognized pattern members in the first direction for a direction pattern or in the angular direction for an axis pattern.
Spacing—Sets the distance between pattern members in the first direction in a direction pattern or the angle between members in the angular direction in an axis pattern.
2—Shows either the translation or rotation pattern creation method in the second direction.
Instances—Sets the number of recognized pattern members in the second direction for a direction pattern or in the radial direction for an axis pattern.
Spacing—Sets the distance between pattern members in the second direction in a direction pattern or the radial distance between members in the radial direction in an axis pattern.
Axis pattern
The commands available for an axis pattern are similar to those available for a direction pattern.
Spatial pattern
Computed Instances counter—Shows the number of pattern members in the recognized geometry pattern.
Tabs
References
Leader surfaces collector—Shows the surfaces that define the leader of the geometry pattern to be recognized.
Details—Opens the Surface Sets dialog box.
Leader curves and datums collector—Shows curves and datums that define the leader of the geometry pattern to be recognized. Datum coordinate systems cannot be selected.
Transform selected attachment rounds/chamfers check box—Includes in the pattern recognition the selected rounds and chamfers that attach the pattern leader geometry to the model. If not checked, the selected attaching rounds and chamfers are removed and optionally recreated.
Options
Allow edit check box—Edits the number of pattern members and the spacing between pattern members for direction or axis patterns. Removes the existing pattern surfaces, and recreates the pattern using only the surfaces that are recognized as part of the pattern.
Restrict pattern recognition check box—Restricts the pattern recognition to a selected region of the model.
Surfaces collector—Shows the surfaces that define the desired pattern recognition region. Members of the recognized geometry pattern must intersect the selected surfaces. Click Details to open the Surface Sets dialog box.
Sketch collector—Shows the sketch that defines the desired pattern recognition region. When the sketch is extruded, members of the recognized geometry pattern must lie within the extrusion of the sketch. Click Define to open the Sketch dialog box.
Pattern
Patterns found menu—Selects which geometry pattern is the recognized pattern. The pattern types available are Direction, Axis, or Spatial.
Computed properties—Shows the computed properties of the selected recognized pattern.
Direction—Shows pattern type, number of members, and spacing between members for the first and second directions.
Axis—Shows the number of members and spacing between members for the angular and radial directions
Spatial—Shows the number of members.
Attachment—Available when Allow edit is selected on the Options tab.
Attach pattern members check box—Attaches all pattern members to the model geometry.
Create rounds/chamfers check box—Attaches all pattern members to the model geometry with rounds or chamfers of the same type and dimensions as the pattern leader.
Properties—Shows the name of the feature. Click to display information in the browser.