To Propagate Annotations in the Same Model
1. Select the feature or geometry, for example, surface offset or surface mirror, that was built on geometry referenced by Annotation Elements.
2. Click
Annotate >
Annotation Features >
AE Propagate. The
Annotation Propagations tab opens and the propagated annotations are visible in the graphics window.
3. Click References.
◦ A panel appears with the
Features,
Surface Sets, and
Chains collectors. These collectors display references that were selected before you clicked
.
◦ The Copy All and Dependent check boxes are selected by default.
4. You can use the Features, Surface Sets, and Chains collectors to add or remove features and references.
5. Click Annotation Elements. The panel displays the list of Annotation Elements that reference the specified features. The check boxes in the Propagate and Dependency columns are selected by default.
| • Clearing the check boxes in the Copy All and Dependency column does not affect the propagation or dependency status of the Annotation Elements that are already present in the list of Annotation Elements in the slide up panel. • If you have specified a feature reference after clicking and clearing the Copy All and Dependent check boxes, then in the slide up panel for the Annotation Elements, the check boxes in the Propagate and Dependency columns are not selected. |
6. In the Propagate column, if the check box next to the Annotation Element name is selected, then the annotation is propagated. If you do not want to propagate an annotation, clear the check box in the Propagate column corresponding to the Annotation Element.
7. In the Dependency column, if the check box next to the Annotation Element name is selected, then the propagated Annotation Element is dependent on the original. You can change the status of the check box in the Dependency column only when the corresponding check box in the Propagate column is selected.
8. On regeneration, if you do not want Creo Parametric to update the propagated Annotation Elements in the Annotation Element propagate feature, then clear the Copy All check box before completing the creation of the Annotation Element propagate feature.
9. On regeneration, if you want Creo Parametric to automatically make the newly propagated Annotation Elements in the Annotation Element propagate feature to be independent, then clear the Dependent check box before completing the creation of Annotation Element propagate feature.
10. Click
. The new Annotation Element propagate feature appears in the Model Tree.