PARAMETER NAME
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DEFINITION
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&d#
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Displays a dimension in a drawing note, where # is the dimension ID.
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&ad#
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Displays an associative dimension in a drawing note, where # is the dimension ID.
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&rd#
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Displays a reference dimension in a drawing note, where # is the dimension ID.
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&p#
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Displays an instance number of a pattern in a drawing note, where # is the pattern ID.
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&g#
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Displays a gtol in a drawing note, where # is the gtol ID.
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&<param_name>
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Displays a user-defined parameter value in a drawing note.
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&<param_name>:att_cmp
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An object parameter that indicates the parameters of the component to which a note is attached.
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&<param_name>:att_edge
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An object parameter that indicates the parameters of the edge to which a note is attached.
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&<param_name>:att_feat
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An object parameter that indicates the parameters of the feature to which a note is attached.
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&<param_name>:att_mdl
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An object parameter that indicates the parameters of the model to which a note is attached.
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&<param_name>:att_pipe_bend
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An object parameter that indicates the parameters of the pipe bend to which a note is attached.
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&<param_name>:att_spool
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An object parameter that indicates the parameters of the spool to which a note is attached.
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&<param_name>:EID_<edge_name>
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An object parameter that references edges.
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&<param_name>:FID_<feat_ID>
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An object parameter that includes a feature parameter in a note by ID.
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&<param_name>:FID_<FEAT_NAME>
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An object parameter that includes a feature parameter in a note by name.
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&<param_name>:SID_<surface_name>
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An object parameter that references surfaces.
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&angular_tol_0_0
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Specifies the format of angular tolerance values in a note from one to six decimal places.
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&sheet_number
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Displays a drawing label indicating the current sheet number.
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&sheet_name
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Displays a drawing label indicating the current sheet name.
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&det_scale
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Displays a drawing label indicating the scale of a detailed view. You cannot use this parameter in a drawing note. Creo Elements/Pro creates this parameter with a view and places it in notes automatically. You can modify its value, but you cannot call it out in another note.
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&dtm_name
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Displays datum names in a drawing note, where name is the name of a datum plane. The datum name in the note is read-only, so you cannot modify it; unlike dimensions, a datum name does not disappear from the model view if included in a note. The system encloses its name in a rectangle, as if it were a set datum.
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&dwg_name
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Displays a drawing label indicating the name of the drawing.
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&format
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Displays a drawing label indicating the format size (for example, A1, A0, A, B, and so forth).
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&linear_tol_0_0
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Specifies the format of dimensional tolerance values in a note from one to six decimal places.
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&model_name
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Displays a drawing label indicating the name of the model used for the drawing.
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¶meter:d
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Adds drawing parameters to a drawing note, where parameter is the parameter name and :d refers to the drawing. .
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&<param_name>:mdl
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Adds a model parameter to a drawing note, table cell, or drawing Program where <param_name> is the parameter name. Using the :mdl suffix prevents the drawing from switching the parameter reference from the model to the drawing (¶meter:d) if the model parameter cannot be located.
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&pdmdb
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Displays the database of origin of the model.
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&pdmrev
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Displays the model revision.
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&pdmrev:d
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Displays the revision number of the model (where :d refers to the drawing).
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&pdmrl
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Displays the release level of the model.
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&scale
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Displays a drawing label indicating the scale of the drawing.
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&scale_of_view_detailed_bar
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&sym(<symbolname )
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Includes a drawing symbol in a note, where symbolname is the name of the symbol.
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&todays_date
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Displays a drawing label indicating the date on which the note was created in the form dd-mm-yy (for example, 2-Jan-92). You can edit it as any other nonparametric note, using Text Line or Full Note.
If you include this symbol in a format table, the system evaluates it when it copies the format into the drawing.
To specify the initial display of the date in a drawing, use the configuration file option "todays_date_note_format."
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&total_sheets
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Displays a drawing label indicating the total number of sheets in the drawing.
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&type
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Displays a drawing label indicating the drawing model type (for example, part, assembly, etc.).
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&view_name
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Displays a drawing label indicating the name of the view. You cannot use this parameter in a drawing note. Creo Elements/Pro creates it with a view and places it in notes automatically. You can modify its value, but you cannot call it out in another note.
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&view_scale
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Displays a drawing label indicating the name of a general scaled view. You cannot use this parameter in a drawing note. Creo Elements/Pro creates it with a view and places it in notes automatically. You can modify its value, but you cannot call it out in another note.
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Pro/REPORT System Parameters
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&asm.mbr.comp....
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Retrieves information about the component from the model data and displays it in the report table.
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&asm.mbr.cparam....
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Retrieves a given component parameter.
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&asm.mbr.cparams....
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Lists information pertaining to all component parameters for the current model.
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&asm.mbr.name
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Displays the name of an assembly member. To show tie wraps and markers, the region attributes must be set to Cable Info.
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&asm.mbr.param....
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Displays information about parameters in an assembly member.
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&asm.mbr.type
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Displays the type (part or assembly) of an assembly member.
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&asm.mbr.User Defined
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Lists the specified user-defined parameter for the respective assembly components. Note that "&asm.mbr." can be used as a prefix before any user-defined parameter in an assembly member.
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&dgm....
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&fam....
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Retrieves Family Table information about the model.
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&harn....
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Shows cable harness parameters for 3-D harness parts and flat harness assemblies.
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&lay....
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Retrieves layout information about the model.
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&mbr....
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Retrieves parameters about a single component.
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&mdl....
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Retrieves information about a single model.
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&prs....
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Retrieves process-specific report parameters used to create reports on the entire process sequence.
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&rpt....
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Displays information about each record in a repeat region.
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&rpt.index
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Displays the number assigned to each record in a repeat region.
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&rpt.level
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Shows the recursive depth of an item in a repeat region.
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&rpt.qty
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Displays the quantity of an item in a repeat region.
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&weldasm....
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Retrieves welding information about the model.
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&asm.mbr.cblprm....
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Lists values for a given cabling parameters.
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&asm.mbr.cblprms....
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Lists values for cabling and wire parameters.
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&asm.mbr.connprm....
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Lists parameters for connector pins in flat harness assemblies.
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&asm.mbr.location...
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Lists the location callouts in a specified view or all views of the drawing in session.
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&asm.mbr.pipe....
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Shows pipeline, pipe segment, and Pro/REPORT bend information parameters.
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&asm.mbr.generic.name….
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Lists the generic name information for a Family Table instance in a table.
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&asm.mbr.topgeneric.name….
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Lists the top generic name information for a Family Table instance in a table when working with a nested Family Table.
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