To Create a Feature of Type Revolve

1. Click Feature >

Revolve on the AutobuildZ tab. The Revolve Feature wizard opens.

2. Specify the name and type of the revolved feature that you want to create on screen Step 1 Of 5 of the Revolve Feature wizard. You can switch between Protrusion and Cut.

3. Under Revolve Axis on screen Step 2 Of 5, click

to select a line entity that defines the axis of revolution.

4. Click

if you want to clear the selection and select the line entity again.

5. On screen Step 3 Of 5, under Section Profile, click

to select entities to define the section profile. The section profile is automatically validated.

Entities that you select to define the section profile and the axis of revolution must be from the same view.

6. Click

if you want to clear the selection and select the entity again.

7. Under Sketch Plane, on screen Step 4 Of 5, click

to select a line entity to define a sketch plane.

The 3D Info box displays the name of the datum plane or surface that the selected line entity represents, if it exists in the 3D model. If the datum plane or surface does not exist, then a new datum plane is created and its name displayed in the 3D Info box.

8. Click

if you want to clear the selection and select the entity again.

9. Click Flip if you want to change the sketch view direction.

10. On screen Step 5 Of 5, specify the angle of revolution by one of the following methods:

◦ Under Angle Reference, select a line entity. The angle between the selected line and the line selected to represent the sketch plane is used as the angle of the revolve feature.

◦ Under Angle Options, select one of the following:

▪

Variable—Specify an angle between 0 and 360 degrees in the adjacent box, or select one of the angles of revolution from the list. This is the default.

▪

To Selected—Is available when you select a line entity of the drawing. The ID of the surface or datum plane that the line entity represents is displayed in the adjacent box.

11. Click

to flip the direction of revolution of the feature.

12. Click Preview to preview the following feature elements in a Creo Parametric window during the relevant step of the revolve feature creation process:

◦ The reference surface or datum plane that represents the sketch plane

◦ The 3D revolve feature when all feature elements are defined