Assembly Design > Top Down Design > Data Sharing > Merge and Inheritance Features > Inheritance Features > To Define Varied Annotations for Geometry Tolerances
  
To Define Varied Annotations for Geometry Tolerances
1. Retrieve an assembly, select a part in it, right-click, and choose Activate.
2. Select a second part in the assembly as the reference model from which geometry will be copied and click Get Data > Merge/Inheritance. The Merge/Inheritance tab opens with the reference model selected by default. You can select a different part as the reference model from the Model Tree or in the graphics window.
3. Click to toggle between Merge mode (default) and Inheritance mode.
4. Click Options.
5. Click Varied Items. The Varied Items dialog box and a separate window showing the Inheritance model open.
6. Click the Geom.Tols tab.
7. Select or clear the Copy All check box to copy all or individual geometry tolerances.
 
* Use the Copy column to define specific annotations. This column overrides the default Copy All status.
8. Select an inherited geometry tolerance. Information about the selected geometry tolerance appears in the Varied Items dialog box.
9. Enter a new value for the geometry tolerance in the New Value text box.
 
* To vary a geometry tolerance property but not the value, type * under New Value.
10. To display the Varied Props column, perform the following actions:
a. Click . The Varied Geometry Tolerance Table Column Setup dialog box opens.
b. Under Not Displayed, select Varied Props, and then click . Varied Props moves to the Displayed section.
c. Click OK. The Varied Geometry Tolerance Table Column Setup dialog box closes.
11. Under Varied Props, perform one of the following actions:
Select the check box to maintain the changed property during the next inheritance feature update.
Clear the check box to override the property change and return to the original property value.
12. Click OK. The geometry tolerances are replaced.