To Create a Boolean Feature
1. In an open assembly, click Component > Component Operations. The Component Menu Manager appears.
2. Click Boolean Operations. The Boolean Operations dialog box opens.
3. Select an operation from the Boolean Operation list.
◦ Merge—Merges components in the assembly, adding material from the Modifying Components to the Modified Models.
◦ Cut—Removes Modifying Components material from the Modified Models.
◦ Intersect—Creates an intersection of material from the Modified Models and Modifying Components.
4. Select an option from the Method list.
◦ Geometry (default)—Creates a boolean feature that references the modifying component geometry.
◦ Features—Copies all features from the modifying components to the modified part. This options is available for Merge and Cut.
5. When you create a boolean feature that references the modifying component’s geometry the following options are available.
◦ Set the type of Update Control:
▪ Automatic update—Updates the boolean feature automatically when the modifying component was updated and in session.
▪ Manual update—Allows manual update of the boolean feature when the modifying components were modified and are in session.
▪ No dependency—Does not update the boolean feature when the modifying components were updated and are in session.
◦ Associative placement—Updates the boolean feature according to placement of the modifying components. Only available for Automatic and Manual update
◦ Transfer References—Transfers references from the modifying components to the boolean feature. Only available for Merge.
◦ Discard modifying components—Deletes the modifying components when the boolean feature is created.
◦ Copy Datum Planes—Copies datum planes to the modified model when the boolean feature is created.
◦ Copy Quilts—Copies quilts to the modified model when the boolean feature is created.
6. Click Preview to display a preview of the resulting geometry.
7. Click OK.