About Extending Chamfer Geometry
You can extend chamfer geometry (pieces) to achieve the preferred chamfers for your model. As you create a chamfer, the chamfer geometry automatically propagates across tangent points and then stops at a non-tangent point. If you need to continue the chamfer geometry, you can extend the chamfer piece up to a patch that you select. The following table illustrates the extend process.
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• You can only extend open chamfer sets. If you want to work with a closed-loop chamfer set, you must first use open the chamfer geometry.
• You cannot extend separate (overlapping) chamfer pieces. To remove one of these pieces, hold down the CTRL key and select the piece, or clear it from its respective collector.
• If you need to extend chamfer geometry at a different point other than a patch, you must define a Stop at Reference transition.
• The system uses an automatic blend to fill the gap around a corner. This blend cannot be modified or deleted. If a blend cannot be added, extend cannot be performed.
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Extending Chamfer Geometry
• The chamfer placement edge reference is selected and the chamfer geometry stops at non-tangent points (a).
• The chamfer piece is selected from the Pieces tab and the trim/extend handles appear (b). As the right handle is dragged to extend the chamfer piece, potential extension geometry appears. Notice that blend transitions are automatically added where a gap exists between tangent points. Also notice that the cursor and handle change during extending.
• Using the potential extension geometry as a guide, the handle is dragged to extend the chamfer piece up to the third patch (c). Notice that the potential extension geometry outline changes color indicating the extent of the extension.
• Release the mouse button, and the chamfer piece is extended up to the patch (d).
1. Edge placement reference
2. Chamfer piece (consisting of three patches)
3. Trim/Extend handles
4. Potential extension geometry (including blend transitions)
5. Chamfer extension
6. Extended chamfer piece